Roughing page

Icon	Name	Description
	Detect (FBM Drill)	Analyzes the solid model and detects features based on the Feature Based Machining (FBM) operation's current parameters. View the results of all detected features and their machining information in the Features page. For more information, please refer to Detection States and Modes in FBM.
	Reselection is not available	Hole Wizard features for a Wizard Holes operation can only be selected in Mastercam for SOLIDWORKS. Contact Mastercam for more information. NOTE Mastercam for SOLIDWORKS is no longer supported starting with Mastercam 2024.
	Preview toolpath operations (FBM Drill/Wizard Holes)	Opens the Toolpath Operations Preview dialog box where you can view the list of operations FBM will generate using the current Features page list.
	Select default formulae file (3D high speed toolpaths)	Lets you select a different *.formula file, which Mastercam uses to calculate default values.
	Save parameters to defaults file	Makes the current toolpath settings the default for future toolpaths of this type. Saves the current values in the toolpath properties pages to the .mcam-defaults file specified in the machine group properties.
	Reload parameters from defaults file	Overwrites the current values in the toolpath properties pages with the toolpath's default parameters. These parameters are reloaded from the .mcam-defaults file specified in the machine group properties.
	Display graphical elements	Enables the display of graphical elements, such as plane labels and geometry colors. In 2D or 3D toolpaths Mastercam also has Display only elements on current page, Display plane labels, and Simplify plane display as options.
	Hide dialog	Minimizes the dialog box so that you can use other Mastercam functions, like changing your shading settings or the graphics window view. When finished, press [Esc] to maximize the dialog box.
	Tool Manager	Opens the Tool Manager. Use the Tool Manager to create and edit tool definitions and to work with tool libraries. When you close the Tool Manager, the toolpath dialog box will reappear just as you left it.
	Feed speed calculator	Opens the Feed & Speed Calculator dialog box where you can modify the calculated feed rate or spindle speed by adjusting the material and tool parameters.
None	Page window	This window displays all of the pages that are available to you, depending on the selected toolpath type. A green check mark indicates pages where data has changed in the current session.
None	Quick View Settings	This window summarizes key toolpath information from the Tool page, Coolant page, and Planes page. It updates automatically as you make changes to the different pages and is always visible.
None	Generate toolpath	When selected, automatically generates the toolpath when you click OK. For more information, refer to Accepting and Generating Toolpaths.
	OK	Generates the toolpath and closes the dialog box. If editing a toolpath, applies the changes and closes the dialog box.
	Apply	Applies your changes to the toolpath without closing the dialog box.
	Cancel	Closes the dialog box and cancels the toolpath creation. If editing a toolpath, any changes to the toolpath are discarded.

Ramp type

Select the type of entry ramp to use from the drop-down list. If the selected option fails, another option will be tried. If all fail then a plunge move will be created.

• Automatic: Calculates entry moves using, in order, line, helical, zigzag, and then profile. The first one that does not gouge is used.
• Line: Creates a line at an angle you specify.
• Helical: Creates a helix at an angle and length you specify.

The other parameters that are available in this section depend on the selected ramp type.

Ramp angle

Enter the angle to apply to a Triangular Mesh roughing entry ramp.

Angle

Enter the angle to apply to a Triangular Mesh roughing entry ramp.

Pitch

Enter the steepness of the ramp.

Center cutting tool

Select this option to start the entry motion from a central point of the current pass.

Max ramp length (tool diameter percentage)

Enter the maximum ramp length for the approach.

Min ramp length (tool diameter percentage)

Enter the minimum ramp diameter for the helical approach.

Minimize approach/retract distance

Minimizes the distance between the tool and stock in the case of open area machining.

Tilt during helix

Orients the tool vector normal to the slice at every point on the helical ramp move. This reduces tool overloading in the adaptive pattern.

Avoid plunge

Machines only pockets where the helical approach can fit.

Max ramp diameter (tool diameter percentage)

Enter the maximum ramp diameter for the helical approach when the tool enters the next slice or pass.

Min ramp diameter (tool diameter percentage)

Enter the minimum ramp diameter for the helical approach when the tool enters the next slice or pass.

Stock clearance (stepover percentage)

Enter the minimum distance from the stock, as a percentage of the stepover, to begin the ramp motion.

Entry feed rate

Overrides the feed rate set on the Tool page, and uses the specified feed rate for entry ramps into the cut.

Entry spindle speed

Overrides the spindle speed set in the Tool page, and uses the specified spindle speed for entry ramps into the cut.

Vertical arc leads

Uses vertical tangential arc moves for the default lead-in/out segments instead of linear leads.

Link clearance

Sets the retract distance for the lifted link between the roughing cuts.

Link length threshold

Specifies the maximum allowed length of the adaptive roughing links. If the length of the link is bigger than the threshold value, the retract link type is applied.

Safe distance

Regulates the distance between the tool and wall during adaptive lifted links creation.

Maximal link radius

Sets the upper bounds for the link radius size. The maximal link radius must be greater than or equal to the Minimal curvature radius.

Link clearance

Enter the amount of lift above the cut the tool retraction will raise during a microlift motion.

Link length threshold

Enter the micro lift length to keep the tool down, instead of retracting into the clearance area.

Safe distance

Regulates the distance between the tool and the wall while creating the adaptive links.

Vertical arc leads

Uses vertical tangential arc moves for the default lead-in/out segments instead of linear leads.